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ptc-2678781-Visitor
1-Visitor
March 30, 2011
Question

Help with Datum Axis creation

  • March 30, 2011
  • 9 replies
  • 2442 views

Bump.


new post:
Thanks. Along the same lines, if I want to create an oblique hole through 2 parts assembled together, what's the best way to do this? I want to lock 2 parts together with a screw going at an angle not normal to any default plane.


_____


old post:
I am trying to create a Datum Axis not normal to any of the default datum planes. Want to create an oblique hole through a part. Is there an easy way to do this? Right now, I need to create several datum planes and several datum axes to accomplish this, and it's messy.


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9 replies

D
DavidFrancis1-Visitor
1-Visitor
March 30, 2011

Yes, and I also want to know why I cannot seem to create an axis at the intersection of two datums? It always wants to go normal....


You used to be able to do this?

David T. Francis

B
BobFrindt1-Visitor
1-Visitor
March 30, 2011
That should work David,

select one plane, hold <ctrl> and select the other plane, then select the
axis command

or

select the axis command then select one plane, hold <ctrl> and select the
other plane

Bob Frindt
Sr. Designer
Parker Hannifin Corporation
Parker Aerospace
Gas Turbine Fuel Systems Division
8940 Tyler Boulevard
Mentor, OH 44060 USA
direct (440) 266-2359
cell: (216) 990-8711
fax: (440) 266-2311
-
www.parker.com



David Francis <->
03/30/2011 01:30 PM
Please respond to
David Francis <->


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Subject
[proecad] - RE: Help with Datum Axis creation






Yes, and I also want to know why I cannot seem to create an axis at the
intersection of two datums? It always wants to go normal....
You used to be able to do this?

David T. Francis


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dgschaefer21-Topaz II
21-Topaz II
March 30, 2011
Select plane #1, hold down control, select plane #2, click axis button.



Doug Schaefer
D
DavidFrancis1-Visitor
1-Visitor
March 30, 2011


Yes, that woprked, thanks guys!


I have been away from it for a long time and the interface has changed dramatically! Sometimes I think I would be better off to not have learned it in the 90's... 🙂
David T. Francis

S
sales31-Visitor
1-Visitor
March 30, 2011

Good morning David:


I know how you feel. I’ve been using Pro/E since version 15 (1995).


I have found that 99% of the time functionality you used in the past is in a newer release it’s just that the menu structure and/or approach to accomplishing something has changed. I always figure there will be a small learning curve with a new release, some more than others. The main thing I find annoying about new releases is that past mapkeys sometimes lose their usage and need to be recreated. If you’re a big mapkey user as I am this can sometimes get involved.


The approach that others have already explained above also works for inserting dtm planes. If you need a dtm plane through an axis at an angle as an example, you can select the dtm plane tool, then select the axis, hold the control key while you select another dtm plane and you can now choose the angle of the dtm plane you’re creating. Intuitive really, just different than in the past.


I heard the other day that the interface on the Creo release that’s scheduled for this June will be different than Wildfire 5. The ribbon menu that is now in the drawing mode of Wildfire 5 will be used throughout all modes. Personally I’m looking forward to it.


Have a terrific day!


Best Regards,







Robert










3D ACCURACY



sales@3d-accuracy.com

www.3d-accuracy.com


















R
rrich1-Visitor
1-Visitor
March 30, 2011
Here is best I can come up with. Create 2 datum points in one feature, create one axis through those two points, create one extruded circle cut sketched on an on the fly datum plane normal to the axis & through one of the points.
[cid:image001.png@01CBEEF2.ABE3F210]
WF4 part attached.

Ron
B
BrentDrysdale12-Amethyst
12-Amethyst
March 31, 2011
Hi DL,
Below is the least feature way of doing the sort of thing you want is to
make an offset coordinate system that I know of. You can do this from your
default CYS and you can set translation and rotation all in the one CYS.
However I find this tends to trip me up so I usually use two offset CYS;
the first is XYZ translated to where I want the centre to be the second CYS
is XYZ rotated to give the compound angle that I want. You can then make an
axis through a CYS line (X or Y or Z).

Hope this helps


Regards, Brent Drysdale
Senior Mechanical Designer
Tait Radio Communications
New Zealand
DDI +64 3 358 1093
www.taitradio.com


N
nrollins2-Explorer
2-Explorer
March 31, 2011
Depending on the situation, sometimes I find it easier to sketch a curve
(line) on a plane at the angle I want and create an axis through that curve.
Although, it does make me feel a little cheap doing that. I wonder how it's
done in Direct Modeling.


P
ptc-2678781-VisitorAuthor
1-Visitor
April 12, 2011

Thanks. Along the same lines, if I want to create an oblique hole through 2 parts assembled together, what's the best way to do this? I want to lock 2 parts together with a screw going at an angle not normal to any default plane.

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