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December 14, 2021
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Insert a plus-minus tolerance into a table

  • December 14, 2021
  • 2 replies
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Hi,

 

I need to write a plus-minus tolrence into a table, how do you do that? 

 

it needs to state: 9.45 (upper) -0.2093 (lower) -0.3153

 

I guess you can write in the text editor but I cant figure out what to write

 

Thanks

Best answer by KenFarley

This has come up a number of times over the decades. Currently, as I see it, there are three ways to do this:

(1) If there is a dimension on the drawing that has the format you wish, just reference that dimension in the table cell.

(2) Type the text into the cell and then format the superscript and subscript bits with the corresponding text formatting selections in the ribbon.

(3) Bring up the Text->Text Editor window and type the text in with the archaic Pro/E "markup" codes: "{0:9.45}{1:@+-0.2093@#}{2:@--0.3153@#}{3:@-@#}"

 

Here's a thorough discussion from long ago:

 

Old text tips discussion 

2 replies

KenFarley
KenFarley21-Topaz IIAnswer
21-Topaz II
December 14, 2021

This has come up a number of times over the decades. Currently, as I see it, there are three ways to do this:

(1) If there is a dimension on the drawing that has the format you wish, just reference that dimension in the table cell.

(2) Type the text into the cell and then format the superscript and subscript bits with the corresponding text formatting selections in the ribbon.

(3) Bring up the Text->Text Editor window and type the text in with the archaic Pro/E "markup" codes: "{0:9.45}{1:@+-0.2093@#}{2:@--0.3153@#}{3:@-@#}"

 

Here's a thorough discussion from long ago:

 

Old text tips discussion 

    Chris3
    Chris321-Topaz I
    21-Topaz I
    December 14, 2021

    If you turn on the config option Tol_display to yes then you can see the +, - variable names. In the example below, tp201 is the plus tolerance and tm201 is the minus tolerance. To see these either open the relations dialog box (Tools -> Relations) or on the model table you can click the model intent fly down and select Switch Dimensions.

    Chris3_0-1639484045824.png

     

    After you have the dimension variable names you can include them on your drawing with the session ID like this &tp201:0 where :0 is the session ID. To find out the session ID read through this thread:

    https://community.ptc.com/t5/3D-Part-Assembly-Design/How-can-I-get-the-Session-ID-in-a-Repeat-Region/m-p/544911/highlight/true#M29795 

    We have a mapkey that imports a version of that text file onto the drawing.

     

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