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pimm15-Moonstone
15-Moonstone
August 5, 2024
Question

Is it possible to set default decimal places on creo drawing?

  • August 5, 2024
  • 4 replies
  • 7432 views

I am using Creo version 7.

 

My system decimal places are 5.

 

My drawing decimal places need to be 3.  

 

Is there a way to set the default drawing decimal places to 3?

 

Presently I need to place all of my dimensions and then when they are placed I need to select each dimension to change them from 5 to 3 decimal places.  I keep thinking that there should be a way to modify the default drawing decimal places whether it be on the drawing template or in the config options but I just never found this.  Just to be clear I need the system decimal places to be 5 as there is a large positional difference on curvature within a given sketch unless the decimal places are increased to preserve the needed position.

4 replies

tbraxton
22-Sapphire II
tbraxton22-Sapphire II
22-Sapphire II
August 5, 2024

Set the value of the default_dec_places configuration option for linear dimension and default_ang_dec_places for angular dimensions to required number of decimal places. Any dimension that you create will appear with the defined decimal places.

B
23-Emerald III
BenLoosli23-Emerald III
23-Emerald III
August 5, 2024

These options are set in your drawing DTL file, not config.pro.

You will need to update any drawing templates as the DTL settings are copied into the templates when opened.

 

    P
    pimm15-MoonstoneAuthor
    15-Moonstone
    August 5, 2024

    Ben: This does sound promising.  I will look for how this would be set up to allow changes and how to make these changes but if you or anyone knows how this could be done it would be very helpful.

    B
    23-Emerald III
    BenLoosli23-Emerald III
    23-Emerald III
    August 5, 2024

    After experimenting and dep looking, I do not find a DTL file setting for drawing decimal places on dimensions. It takes the default from the modeling decimal places.

    Options are to create the dimensions with the modeling decimal places and then change the formatting to 3 decimal places or set the modeling decimal places to 3 places and then change them in your modeling mode to 5. When a drawing is created, the dimensions come in with 3 decimal places. Maybe a mapkey to change from 3 to 5 to make it easier,

    It does seem that this should be a standard DTL file setting independent of the modeling decimal places.

    M
    MartinHanak24-Ruby III
    24-Ruby III
    August 6, 2024

    Hi,

    I tried something...

    I created simple model (a block) and its drawing. The drawing contains one view, shown dimensions (driving) and created dimensions (driven).

    If I change decimal places of shown dimension then Creo changes dimension color and after regeneration model geometry is modified.

    If I change decimal places of created dimension then everything works as you need.

      tbraxton
      22-Sapphire II
      tbraxton22-Sapphire II
      22-Sapphire II
      August 6, 2024

      As posted above: "If you are using annotations from the model vs creating dimensions in the drawing you may need to alter the approach to get exactly what you need."

       

      Creo makes a distinction between dimensions created in the model, annotations, and dimensions created in a drawing.

       

      @MartinHanak has done some testing for you and it would appear found a solution.

      S
      Srinivasan-Iyer14-Alexandrite
      14-Alexandrite
      August 6, 2024

      I am on Creo 9.x.x.x

      While rummaging through the help files I came across this page. Hope this helps. I must admit that I have not tried it since the number of decimal places are set to 3 in my case.

      https://support.ptc.com/help/creo/creo_pma/r9.0/usascii/index.html#page/detail/About_Setting_Decimal_Places_for_Dim_Tol_Values.html# 

      Srinivasan_Iyer_0-1722943829320.png

       

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