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wfalco16-Pearl
16-Pearl
December 31, 2019
Solved

Item Number (Find Number) and Part Number in Notes

  • December 31, 2019
  • 1 reply
  • 9085 views

Seasons Greetings:

 

I am pretty sure I can NOT put an Item Number (Find Number) in a note. But at the very least I would like to add the "part_number" parameter. In case below that is "MS20995-C32". This should be as easy as:

 

&asm.mbr.PART-NUMBER MS20995-C32

 

-----

1. APPLY SAFETY WIRE FN (99) (MS20995-C32) USING DOUBLE TWIST METHOD PER
NASM 33540.

-----

 

?

Does not work. I am missing some simple syntax I am sure.

Anyone know?

 

If Item number is possible that would be great to know as well. But I think that's a dead horse?

 

Happy New Year All!

WayneF

Creo 4.0 m020

Best answer by MartinHanak
@wfalco wrote:

Seasons Greetings:

 

I am pretty sure I can NOT put an Item Number (Find Number) in a note. But at the very least I would like to add the "part_number" parameter. In case below that is "MS20995-C32". This should be as easy as:

 

&asm.mbr.PART-NUMBER MS20995-C32

 

-----

1. APPLY SAFETY WIRE FN (99) (MS20995-C32) USING DOUBLE TWIST METHOD PER
NASM 33540.

-----

 

?

Does not work. I am missing some simple syntax I am sure.

Anyone know?

 

If Item number is possible that would be great to know as well. But I think that's a dead horse?

 

Happy New Year All!

WayneF

Creo 4.0 m020

Hi,

 

1.] &asm.mbr.part_number notation is related to repeat region, only

 

2.] do following test

> create new drawing

> set part containing part_number parameter as drawing model

> create drawing note and put &part_number callout in it

 

3.] if drawing model is assembly, you have to use &part_number:session_id callout

 

1 reply

M
MartinHanak24-Ruby IIIAnswer
24-Ruby III
January 1, 2020
@wfalco wrote:

Seasons Greetings:

 

I am pretty sure I can NOT put an Item Number (Find Number) in a note. But at the very least I would like to add the "part_number" parameter. In case below that is "MS20995-C32". This should be as easy as:

 

&asm.mbr.PART-NUMBER MS20995-C32

 

-----

1. APPLY SAFETY WIRE FN (99) (MS20995-C32) USING DOUBLE TWIST METHOD PER
NASM 33540.

-----

 

?

Does not work. I am missing some simple syntax I am sure.

Anyone know?

 

If Item number is possible that would be great to know as well. But I think that's a dead horse?

 

Happy New Year All!

WayneF

Creo 4.0 m020

Hi,

 

1.] &asm.mbr.part_number notation is related to repeat region, only

 

2.] do following test

> create new drawing

> set part containing part_number parameter as drawing model

> create drawing note and put &part_number callout in it

 

3.] if drawing model is assembly, you have to use &part_number:session_id callout

 

W
wfalco16-PearlAuthor
16-Pearl
January 2, 2020

Martin,

 

Happy New Year!

 

Yes. Session ID works. I am finding ID thru a round about way using Excel. I queried the ID number and it was incorrect. So in Excel I ran column down to like 1200 lines:

 

part_number:1

part_number:2

part_number:3

etc.

 

When pasted into Creo - it exposed all ID's. The ones that don't exist, it blows out the & in front of the line.

 

So - this works. But I have to visually find each one. Which is not too bad.

 

NOW....I want to make sure I am assuming that the Session ID WILL NEVER CHANGE- CORRECT?

 

Thanks,

 

Wayne

M
MartinHanak24-Ruby III
24-Ruby III
January 2, 2020
@wfalco wrote:

Martin,

 

Happy New Year!

 

Yes. Session ID works. I am finding ID thru a round about way using Excel. I queried the ID number and it was incorrect. So in Excel I ran column down to like 1200 lines:

 

part_number:1

part_number:2

part_number:3

etc.

 

When pasted into Creo - it exposed all ID's. The ones that don't exist, it blows out the & in front of the line.

 

So - this works. But I have to visually find each one. Which is not too bad.

 

NOW....I want to make sure I am assuming that the Session ID WILL NEVER CHANGE- CORRECT?

 

Thanks,

 

Wayne

Hi,

1.] Session ID is dynamic value related to current Creo session.

2.] Once you set up Session ID, you don't have to worry about it anymore ... Creo changes its value automatically if necessary.

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