&model_name

Forum|Forum|7 years ago
April 25, 2019
3 replies
2890 views

I want to include the part number within a title block so it displays properly on a detail drawing. I want to use &model_name with .PRT at the end so show the extension or .ASM if it's an assembly. Any ideas. I know I've seen it thru out the years.

Bart Brejcha

Design-engine.com

2D Drawing

B

BillChapman

13-Aquamarine

We use &type in the formats. This will give you PART, ASSEM, etc, but not prt, asm

KenFarley

21-Topaz II

So, with this bit of info, a possible solution to the original problem could be to use some relations to define a drawing parameter that is then used in the title block:

(1) Define a drawing parameter, let's call it "partname", with type STRING.

(2) Put in some relations to build the parameter up from the known data:

partname = &model_name
IF &type == "PART"
 partname = partname + ".prt"
ENDIF
IF &type == "ASSEM"
 partname = partname + ".asm"
ENDIF

(3) In your title block, use &partname rather than &model_name.

Keep in mind I'm just using the information you provided, I am not sure of the spelling of the "official" parameters and their possible settings. There might be additional &type variants I don't know, etc.

T

TomU

23-Emerald IV

@bbrejcha,

Some new repeat region parameters were added to Creo 5 that makes doing this very simple. Follow the same concept that @KenFarley suggested, but place the relations inside a single cell repeat region on the drawing.

Repeat Region Parameters.PNG