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Vermont_9514-Alexandrite
14-Alexandrite
November 18, 2020
Question

"Please confirm the temporary removal of upper-level assembly features" message

  • November 18, 2020
  • 2 replies
  • 3473 views

When I acitvate a sub-assembly I get this message

 

Please confirm the temporary removal of upper-level assembly features.

there is no external references visible, non CRC

can someone telle me why I get this message?

thanks

 

Veronique

2 replies

StephenW
StephenW23-Emerald III
23-Emerald III
November 18, 2020

When you activate a sub-assy or a part in an assembly with "assembly features", creo temporarily turns off those assembly features.

V
Vermont_9514-AlexandriteAuthor
14-Alexandrite
November 18, 2020

Hi

 

Sorry but how can I find thoses assembly features.?

We don't use assembly features exept datums
I don't know where to find this related assembly feature

 

regards

 

Veronique

 

StephenW
StephenW23-Emerald III
23-Emerald III
November 18, 2020

Assembly datums don't apply.

These would be assembly revolves/holes/extrudes defined in an assembly.

I don't know the best way to find them. If the assembly isn't too big, just look thru the model tree for a feature that is in an assembly. The one in the image below that is highlighted yellow is the actual assembly cut (hole feature).

The one highlighted in red is how that assembly cut shows up in a part that the assembly cut actually cuts.

You can also use the FIND tool, use Look for : feature, Look by: feature, Attributes: Type, Criteria: Value =Assembly Cut (see image below). It shows the parts affected by the assembly cut.

Hope this helps

 

StephenWilliams_0-1605709406490.png

StephenWilliams_1-1605712082717.png

 

 

tbraxton
tbraxton22-Sapphire II
22-Sapphire II
November 18, 2020

Use the search tool in an assembly containing the part of interest. If there is a structure of subassemblies you will have to modify the search protocol as needed.

 

In this trivial example there is a single solid geometry feature created in the assembly (hole1) which intersects all three plates. The search tool example shows how to find any feature with solid geometry within the assembly (note that the search is constrained to the assembly only). You can build and save search queries if you need to do this repeatedly on multiple assemblies.

 

This example query is based on your statement that other than datum features you do not use assembly features so by finding features with solid geometry that should find any feature affecting geometry of components within a given assembly.

 

 

 

Find assembly features with solid geometryFind assembly features with solid geometry

 

    StephenW
    StephenW23-Emerald III
    23-Emerald III
    November 18, 2020

    This is much better and gets right to the point. Mine only show the "symptoms" of the problem!

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