showing weight for assembly simplified rep on drawing

Hello 

I don't think we can calculate the weight according to the reps. Because the reps are for large assembly management.

To get the weight of specified part you can use family table , instance option .

I would think this is a bad thing to do, but...

There is a config.pro option:

force_upd_assem_mp_in_simp_rep YES

By default, it will not update the mass based on what simplified rep you have open. You will need to add the option and set it to YES.

After adding the option to the config, regenerate your model and it will update your weight.

***WARNING**** If you are the only one with this config option set or you change the option, the next time this drawing is opened, it will revert back to the master rep weight.  Also, this is a system setting, so all your models will updated the mass based on the config change.

I would consider creating a "design assembly (DA)" that serves as a model used to calculate the mass properties you need. If you need anything other than mass, then make sure the parts are located and oriented consistent with design intent. This assembly is only used for design and would not be included in any BOM etc.

Once you have the DA you can create analysis features in the parts and assembly that will facilitate the use of any measured/calculated quantities in the analysis features. If you add this model to the drawing models of a drawing you can access all of the parameters as needed to automate data entry in notes/tables. You would not have to create any drawing views using the DA.

IME this is more robust than family tables or simplified reps in this context, especially if all of your Creo users using the data are not highly trained and competent.

Just putting this out there again.  I can get the weight of a Simplified Rep, but how can I show it automatically on a drawing?  Maybe with a repeat region of some kind?