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PetePickettII14-Alexandrite
14-Alexandrite
March 22, 2022
Solved

Simple table with a parameter, can not be shared with other drawings

  • March 22, 2022
  • 8 replies
  • 2569 views

So I'm having a major brain fart but searching the PTC site for 20 min is getting me nowhere.

Using Creo 5.

I have a simple table, no repeat region.  I want one cell to reflect &customer_name  (or any other basic parameter)

This works but  in this drawing only.   As soon as i save the table and open it in another drawing it wont work.

the table shows CUSTOMER_NAME:1 when it is brought into another drawing

Am i missing something?

Best answer by TomU

Copy the table to an empty drawing that doesn't have a parent model.  Then change any of the session id values to ":MDL" and re-save the table.  The other option is to copy it to an empty format.  Table parameters are not evaluated in a format, so you probably could even skip the "MDL" syntax altogether.  Just remember to save your table back out when finished editing it.

8 replies

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BenLoosli23-Emerald III
23-Emerald III
March 22, 2022

Adding the table to the additional drawings by the Table from file button?

Customer_name is in your additional file? Typically the cell going to the text of the parameter is caused by the system not finding the parameter name.

 

It works fine in Creo 7.0.7.0.

KenFarley
KenFarley21-Topaz II
21-Topaz II
March 22, 2022

Are you copying the table from one drawing to another via Copy/Paste? If so, it might be similar to what happens when I copy/paste a note that uses parameters into another drawing. I think it's something to do with the fact that the parameter will have the Session ID appended onto it from the original part in its drawing (i.e. "CUSTOMER_NAME:1") like you show. When it's pasted into the new drawing, it doesn't "see" the same part in that drawing, so it usually shows as "***" rather than the parameter value for the new part.

When I copy a note from one drawing to another I always have to retype in the &parameterName callout where the three asterisks are and Creo then puts the right text in there.

Also, don't append the ":1" or whatever when typing the parameter in the new drawing. Creo will figure it out and put the right number on the end based on which model is active at the time. This stuff is kind of confusing, I suppose.

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TomU23-Emerald IV
23-Emerald IV
March 22, 2022

To make the table work in other drawings, you need to use a syntax that doesn't tie the parameter to a specific session id.  This can be done by using the &parameter:mdl syntax.  When this table is added to another drawing, the :mdl portion will automatically convert to the session id of the new drawing's parent model (assuming that parameter actually exists in the parent model.)

 

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    PetePickettII14-AlexandriteAuthor
    14-Alexandrite
    March 22, 2022

    Tom how do i get the table to save the :MDL at the end of that string?  Or are you just saying PTC needs to enhance this functionality to allow it?

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    TomU23-Emerald IVAnswer
    23-Emerald IV
    March 23, 2022

    Copy the table to an empty drawing that doesn't have a parent model.  Then change any of the session id values to ":MDL" and re-save the table.  The other option is to copy it to an empty format.  Table parameters are not evaluated in a format, so you probably could even skip the "MDL" syntax altogether.  Just remember to save your table back out when finished editing it.

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