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PierrePatenaude1-Visitor
1-Visitor
November 4, 2016
Question

User-defined parameter in notes in format

  • November 4, 2016
  • 4 replies
  • 3025 views

I want to place user defined parameters in notes, which are placed in a drawing format file. The user defined parameters are set in part and assembly files. When I create a drawing with that format, the user defined parameter, located in a note, don't show its value. Instead it shows the parameters name.

In that same drawing with that same format, the user defined parameters that are placed in tables are working fine - they show the parameter values.

In that same drawing with that same format, the system parameters that are placed in notes are working fine - they show the parameter values.

I have tried reloading the format in the drawing and that doesn't change anything.

I have tried adding ":mdl" at the end of the parameter value placed in the note and that doesn't change anything.

Is it possible that user defined parameters in notes, in a format files don't work?

We are on Creo 2.0. We don't have Windchill.

Thanks


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4 replies

B
BenLoosli23-Emerald III
23-Emerald III
November 4, 2016

They have to be in a table to show on a drawing.

I wish they would show on the drawing without being in a table, too.

    M
    mender12-Amethyst
    12-Amethyst
    November 4, 2016

    You can kind of fake it by making a table with a 0.00000001 inch cell.  But really, what you ought to do here is have this note in a drawing template, not a format.  The idea of format is that it is the same (except the tables, which are copied over) in the format and the drawing.

    Alternatively, you could conceivably make a use case for designating certain notes on the format to be copied over to the drawing like tables are, and propose that.  Be sure to point out why the standard approach 'using a drawing template for that' wouldn't work well for your case.

      P
      PierrePatenaude1-VisitorAuthor
      1-Visitor
      November 4, 2016

      Placing the notes in the format prevents the user from moving them around. In a drawing template the notes can be edited and moved.

      So I understand that this is a Creo limitation and the workaround is to place the notes in the drawing template instead of placing them on the format.

      But it still remain a mystery to me why this works for the system parameter and not for the user-defined parameters.

      K
      Kevin1-Visitor
      1-Visitor
      November 5, 2016

      ‌Because user defined parameters contained in a model are not present in the format the text you enter, &parameter_name, gets automatically converted to plain text so the formatting isn't kept. With a template a model is usually associated with it. Tables and repeat regions in a table keep the text formatting.

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