Two views assembly configurations on one drawing

Question

Good morning,I have one assembly and I'd like to show it in two configurations, one with a part constrained to a 45º and another with the same part at a 90º angle.I have tried to do this with Simple Reps but to no avail.I first tried to give the angle constaint a different value in each representation but it changed throughout all SRs.I then tried to have two angle constraints, enabling and disabling per SR but again the enabling and disabling changed throughout all SRs.Any advice gratefully received.This thread is inactive and closed by the PTC Community Management Team. If you would like to provide a reply and re-open this thread, please notify the moderator and reference the thread. You may also use "Start a topic" button to ask a new question. Please be sure to include what version of the PTC product you are using so another community member knowledgeable about your version may be able to assist.

jsarkar · Accepted Answer

You should use snapshot instead of simplified representation. Lets make the angle 45 deg, then u open drag components and click on save snapshot. right click on snapshot and make toggle for drawing. similarly do for other configurations.

Now in the drawing, place view and properties box u check for exploded views and selecte the snapshots.

https://www.ptc.com/appserver/cs/view/solution.jsp?n=CS30049&posno=2&q=snapshot in drawing&nav=ptcproductgroups||||Product+Group||&source=Search

rreifsnyder · Answer

HUGE DISCLAIMER: As with most things with Pro/E there are numerous ways to accomplish a task, The optimal choice may depend on many factors regarding what output you need and how it will be tracked.

If you just need to see the component at those 2 places, I would stay away from both mechanism and snapshot. Mechanism is one of those tools that has great power but in my opinion is overhead when you just need to see a component(s) at discrete positions. Snapshot will not update the view automatically when design changes happen and to update you will have to put the assembly back in that configuration to update the views that use those configurations.

I know family tables have a horrible reputation but this is the type of example when it may be the most appropriate course.

The way to do this with a simplified rep would be to use a technique called "overloading". Using this technique the same component is assembled at each position you need to see it in, then use simp rep to see only one at a time.

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