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mmueller-21-Visitor
1-Visitor
November 18, 2015
Question

Mirror Part

  • November 18, 2015
  • 4 replies
  • 11979 views

Hi,

is there any way to choose the mirror plane when I want to save a mirrored part?

I use Creo 3 M60.

If not - PTC just do it!

Many thx,

Michael

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    4 replies

    D
    dgschaefer21-Topaz II
    21-Topaz II
    November 19, 2015

    Nope.

    D
    dgoodland12-Amethyst
    12-Amethyst
    December 8, 2015

    Yes there is! IF you create the mirrored part inside an assembly.

    1. In the "Component" area of the "Model" tab ... you pick "create"
    2. the Create window opens, you choose "Part" with the radio selected for "Mirror" (Give it a Name & Common name)
    3. Next window, select your mirror type... Dependency control ... the Part you are mirroring ... and most important - the Plane to mirror from
    4. Preview it with the check box option at the bottom left... then hit "okay" when you're done

    I haven't yet checked the dependencies in Windchill. But this is the only way to select the mirror plane I know.

    UPDATE: It worked perfectly in Windchill - as long as the mirroring plane you chose was in the part itself, there was no assembly dependency.

      C
      CoreySusie1-Visitor
      1-Visitor
      January 7, 2016

      In my previous experience it would only mirror across that plane within that assembly for that one component.  Once you took that same component out and to another assembly or assemble it again at Default it would act as if it was mirrored across the front datum plane.

      What you can do to remedy this is to:

      1. Create a new part
      2. Copy Geometry from original side
      3. Mirror Copy Geometry quilt
      4. Solidify mirrored quilt across the datum of your choosing
      5. Hide Copy Geometry

      Now you have a dependent mirrored version across the plane of your choosing

      M
      mmueller-21-VisitorAuthor
      1-Visitor
      January 12, 2016

      This is the way i do it for now. I thought save as mirror part with a plane to choose could be simpler.

      Many thanks for all the answers and tips, so far.

      Michael

      T
      TomD.inPDX17-Peridot
      17-Peridot
      January 8, 2016

      I know I have a desire to be able to do this, but I always remember that no part file has a specific orientation by itself, and assemblies orient the parts.

      Is there a specific reason this is needed?

      Of course; knowing you are going to do this, you can plan ahead and build your model with the default mirror plane in mind.

      Doug's answer is correct

      D
      dgoodland12-Amethyst
      12-Amethyst
      January 8, 2016

      Did you try my solution? Because I've used it now twice completely successfully in Creo 2.0 with Windchill 10.2.

      C
      CoreySusie1-Visitor
      1-Visitor
      January 8, 2016

      Daniel,

      This is how it had to be done prior to Wildfire 3.0 when File->Mirror Part was introduced.

      However you will find upon further investigation using your method it will mirror about the Front Plane regardless of what plane you chose.

      I
      ifomenko1-Visitor
      1-Visitor
      September 25, 2018

      It`s still impossible in Creo 5, but it`is possible to use flexible modeling to rotate body about some axis just after

      save as->mirror operation

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