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ptc-46001851-Visitor
1-Visitor
July 19, 2013
Solved

Exploded lines in drawing's view

  • July 19, 2013
  • 2 replies
  • 16164 views

Hello,

I have a problem with the lines of an exploded assembly when I represent a exploded state in a drawing in a shaded mode. The lines are always at top-level even if they are hidden by another part (see pictures). This problem does not appear in other view modes.

Anyone can help?

Thank you,

Thierry


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Best answer by TomD.inPDX

I just came up with a work-around if this is important to you.

  • I created an exploded view and extension lines in the assembly model. These lines are called "offset line" in the model tree if you show the features.

  • Assign these offset lines to a layer in the assembly model in order to hide them easily.

  • Save your preferred orientation for the drawing view.

  • Open the drawing, place the view and edit the origin of the view (to some nice round number).

  • Change the view display to No Hidden (this will trim the extension lines).

  • Create a new view set to Shaded (no-edges) located at the same origin.

  • Switch the drawing tree to layer tree and set the layer to the shaded view name.

  • Hide the layer you created with the Offset Lines on it (this will hide the layer only in that view).

Now you will have a shaded view with a no hidden overlay which trims the extension lines.

view_overlays.PNG

2 replies

T
TomD.inPDX17-Peridot
17-Peridot
July 19, 2013

Hello and welcome to the forum.

It appears that only hidden line removal will change the state of the extension lines in exploded views.

It seems silly to not use the hidden line state for shaded image. This would be a simple algorithm change for PTC. Maybe you can post this as an Idea.

    T
    TomD.inPDX17-PeridotAnswer
    17-Peridot
    July 19, 2013

    I just came up with a work-around if this is important to you.

    • I created an exploded view and extension lines in the assembly model. These lines are called "offset line" in the model tree if you show the features.

    • Assign these offset lines to a layer in the assembly model in order to hide them easily.

    • Save your preferred orientation for the drawing view.

    • Open the drawing, place the view and edit the origin of the view (to some nice round number).

    • Change the view display to No Hidden (this will trim the extension lines).

    • Create a new view set to Shaded (no-edges) located at the same origin.

    • Switch the drawing tree to layer tree and set the layer to the shaded view name.

    • Hide the layer you created with the Offset Lines on it (this will hide the layer only in that view).

    Now you will have a shaded view with a no hidden overlay which trims the extension lines.

    view_overlays.PNG

      P
      ptc-46001851-VisitorAuthor
      1-Visitor
      July 22, 2013

      Thank you for the workaround I got what I wanted 🙂

      I will forward the issue to PTC for an idea.

      Best regards

      Thierry

      Patriot_1776
      Patriot_177622-Sapphire II
      22-Sapphire II
      July 22, 2013

      Honestly, offset lines are a total pain to use. What I've started to do is simply make the lines as parametric sketched lines in the dwg. Much easier, and faster, and the dwg is the only place you use them anyways.

      T
      TomD.inPDX17-Peridot
      17-Peridot
      July 23, 2013

      It really is a very poor 3D sketcher. Had PTC done something with 3D curves back in WF, this should have been a breeze. Just the fact that you cannot pick the center of a hole or intelligently move a whole line is infuriating.

      Patriot_1776
      Patriot_177622-Sapphire II
      22-Sapphire II
      July 23, 2013

      Yup. I refuse to use them anymore. Though the 2D sketcher in dwg mode sux, it's still a lot easier to make the lines there.

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