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tbraxton
22-Sapphire II
tbraxton22-Sapphire II
22-Sapphire II
February 23, 2021
Solved

How to change the number of decimal places for all model dimensions

  • February 23, 2021
  • 4 replies
  • 16168 views

I want to change the display of all dimensions in a previously built model to 3 decimal places in part mode.

PTC support documents the following steps to do this. I follow until step 6. Where is there a format tab and column in part mode? Menu mapper is not finding it and doc search is not fruitful. Can anyone elaborate on step 6 below?

 

In Creo Parametric 3.0 and later versions:

    1. Ctrl+F or Tools > Find
    2. Set Look for and Look by to Dimension
    3. Click Find Now
    4. Click in the items found area and click Ctrl+A to select all dimensions
    5. Click the arrows icon to transfer items from items found to the Items Selected section of the Search Tool dialog box > Click Close
    6. Change the Decimal Places value as desired in Format column in Format tab

 

Best answer by tbraxton

The root cause of why this process was not working for me is that I was including pattern members in the find tool selection process (step 5). If any pattern members are selected that do not have dimensions then the dimension tab will not activate. This is intended functionality according to PTC.

 

The work around is to not select any pattern members in the find tool for selection (in step 5) then the dimension tab will be available and you can set the number of decimal places to be displayed. You can include pattern leaders that have a dimension in step 5 and it will still work but you need to insure that there are no features without a dimension selected in step 5.

4 replies

T
23-Emerald IV
TomU23-Emerald IV
23-Emerald IV
February 23, 2021

In Creo 6 it would be the 'Dimension' tab, but I'm have trouble getting it to appear just from the search results.  Even if I select one dimension and get the tab to appear, searching for additional dimensions and adding them to the selection set makes the tab disappear.  Hmmm...

S
23-Emerald III
StephenW23-Emerald III
23-Emerald III
February 23, 2021

I'm on Creo 4.

When I finish step 5, it shows me all the dimensions and automatically shows the "Dimension" tab and I can set the # of digits there. I don't see a format tab either, at least not in Creo 4.

 

StephenWilliams_0-1614096685692.png

 

T
23-Emerald IV
TomU23-Emerald IV
23-Emerald IV
February 23, 2021

I believe the dimension tab replaced the format tab.  PTC probably just hasn't kept the article up to date.

kdirth
21-Topaz I
kdirth21-Topaz I
21-Topaz I
February 23, 2021

In Creo 4 I can select any or all dimensions and will get the dimension tab unless something in the model is suppressed.

 

I don't see a way to limit the Find feature from finding dimensions in suppressed features.

 

There is always more to learn.
kdirth
21-Topaz I
kdirth21-Topaz I
21-Topaz I
February 23, 2021

I have found that, for whatever reason, precision (the section needed) is greyed out when an angle is included in the selection.  Looks like a program bug.

There is always more to learn.
    tbraxton
    22-Sapphire II
    tbraxton22-Sapphire IIAuthor
    22-Sapphire II
    February 23, 2021

    I just tested this and if the part has any angular dims the dimension tab is not activated or displayed. I am in Creo 4 M110 testing this. Creo 7.0.3 is also not working correctly, I just opened a case with support. I will post the response here when it comes.

    tbraxton
    22-Sapphire II
    tbraxton22-Sapphire IIAuthorAnswer
    22-Sapphire II
    March 3, 2021

    The root cause of why this process was not working for me is that I was including pattern members in the find tool selection process (step 5). If any pattern members are selected that do not have dimensions then the dimension tab will not activate. This is intended functionality according to PTC.

     

    The work around is to not select any pattern members in the find tool for selection (in step 5) then the dimension tab will be available and you can set the number of decimal places to be displayed. You can include pattern leaders that have a dimension in step 5 and it will still work but you need to insure that there are no features without a dimension selected in step 5.

    T
    23-Emerald IV
    TomU23-Emerald IV
    23-Emerald IV
    March 3, 2021

    I also opened a case to push tech support to update the article.  The whole point of the middle section is to update *ALL* model dimensions.  If there are certain types of dimensions that mess up this process (pattern members, suppressed, angular, etc.) and prevent display of the 'Dimension' tab, then the article needs to explain how to adjust the search results so these aren't inadvertently included.

    tbraxton
    22-Sapphire II
    tbraxton22-Sapphire IIAuthor
    22-Sapphire II
    March 3, 2021

    I spoke with support earlier today. I provided the article # when I opened a call last week and they committed to updating it and adding information about features without dims to the article.

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