SOAP Client Error

We also receive this error message, but cannot find the cause.

we are running WF4.0 M090 on Windchill 8.0 M050.

The problem could be stemming from the data set the user is trying to load, a large assembly that strains the limit of a 3GB 32 bit XP system. there are many shrink wraps and other practices that this company deems unacceptable. However, there is no clear solution from PTC.

Any insight would be much appreciated.

If I recall correctly, the system needs X amount of memory to keep a connection with PDMLink (in our instance). When the system memory approaches the limit (~3GB with 32bit OS) it no longer has enough memory to keep the connection alive. You should see a "Server Offline" message which will almost instantly tell you it is once again available as soon as you click the message box.

How much memory is in the machines?

Are you running the 3GB switch?

Hi All,

Although the suggestions above are all valid in the quest for a stable workspace i have found over time that the problem lies within the data set. if you are frequently receiving SOAP errors take a look in the Global Reference Viewer of Pro/E and you will see red X's on the Parent side of the relationship. Take the time to resolve these missing references, crc loops and dummy references, it will pay for itself by all of the users that need to regenerate this data set. Training and constant mentoring is required for all high end CAD systems, w

Invest in your data, it is your product definition not "just a drawing".

Enjoy this tongue and cheek document, it is part of my intenal Wiki for Pro/E users.

Commandments of Pro/E

(These are good generalized rules downloaded from a Pro/E user group email. Note: As in life there is no one way to do something and there is no one rule to explain everything)

Part Mode

I. Thy Holes and cuts shall not be filled.

II. Thy Features shall not be covered completely by other features

III. Thou shall add chamfers, drafts, and rounds at the end of the model and not create children of chamfers, drafts, and rounds

IV. Thou shall avoid creating rounds and chamfers in sketcher, as they should be added as separate features, when possible.

V. Patterns shall be used in preference to copy

VI. Thou shall keep sketches simple and not create complex features with a single sketch

VII. Thou shall name thy features to ease future redefinition

VIII. Incomplete features shall be removed or completed

IX. Thou use thin sections when applicable

X. Thou shall always keep the same parent surface for thy merges.

XI. Thou shall use datums to define depth of feature when feature depth is likely to change, and feature will have plenty of children

XII. Thou will have problems with drafts and rounds

XIII. Thou shall reference datum features in sketches wherever possible

XIV. Thou shall fix missing reference warnings immediately

Drawing Mode

I. Thou shall not use Snapshot, unless required in dire need

II. Thou shall use shown dimensions as much as possible

III. Only Company standard formats shall be used on drawings

IV. Thy drawings shall not contain overwritten dimensions (@o)

V. Models attached to Thy drawings, but not showing in any views, shall be removed

VI. Thou shall Orient views using default datums or view names, not thy model geometry

VII. Thou shall make the drawing independent of local environment settings

Assembly Mode

I. Thy alternative components shall not be left assembled on top of each other

II. Thy Assembly features, such as cuts, shall be avoided

III. Thou shall use constraints that reflect real-life assembly or manufacturing situations

IV. Thou shall follow the rule that assembly datums make the best parents

V. Thou shall not select constraints simply based on ease of selection of references

VI. Thy Frozen components shall be resolved

PDM/LINK

I. Thou shall not submit parts and assemblies to PDM/LINK with suppressed features and components

II. Thou shall not submit parts and assemblies to PDM/LINK in insert mode

III. Thou shall verify all instances before Check-In

IV. Thy regen status shall be green

General

I. All thy applicable parameters shall have a value assigned

II. Thou shall orient sketches the same way within a model e.g. always set TOP, RIGHT, or FRONT as "TOP".

III. Thou shall use default datum planes to orient sketches unless there is a damn good reason not to

IV. Thou shall use start parts & Assemblies for all new models

V. Thou shall clearly comment all relations

VI. Thou shall learn to love Layers and his more advanced brethren, Simplified Rep’s

VII. Thou shall not make any unintended parent-child relationships or you will suffer the wrath at the hands of redefine, reroute, and reorder. The use of "query select" or "select by menu" shall be used if there is any doubt as to which entity you are selecting, to ensure correct parent/child relationship

VIII. Thou shall use the erase option to clear objects from memory and shall not be confused with the delete option.

IX. Thou shall save early and often

X. Thy Circular References shall be resolved

XI. Thou shall learn to create multiple datums-on-the-fly

XII. Thou shall limit points on splines.

XIII. Thou shall save parts with axes, points, surfaces, planes, geo tol, coords, blanked.

XIV. Thou shall consider too many datum features (planes, curves, points) as never enough and unused datums shall be deleted

XV. Thou shall not family tables for anything accept a true family, such as fasteners

XVI. Thou shall never reference a model edge if there is a suitable surface available

XVII. Thou shall not use cosmetic sketches”