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NE_106470331-Visitor
1-Visitor
April 6, 2023
Solved

Thicken surfaces. Issues with making 2 thickend surfaces line up with eachother.

  • April 6, 2023
  • 3 replies
  • 3542 views

Hi!

I am working on a school project where we are using surface modeling to create a hair dryer suitable for injection molding (We are and have to work in Creo 4.0, just fyi). I decided to go for a more advanced modeling method where I make a boundary blend towards a projection on a complex "pane"/surface (as can be seen in image below).

NE_10647033_0-1680780259623.png

 

I use a ribbon as a tangent for the boundary blend, I create the ribbon with sketches and curves. The splines in the sketches are tangent to a horizontal center line, while the curves are tangent to axis that are perpendicular to the vertical plane. I do the same for the for the handle (see below).

NE_10647033_2-1680780402252.png

I then merge and thicken this. I use the top-down approach to make the back half referencing the relevant points of the front half. Lastly to my point and my issue, the thicken (even tough all boundary blends uses tangency to ribbons that where created with sketches and curves that are constrained in such a manner that they are perpendicular to the vertical plane) is not created evenly and tangentially which leads to the front and back half interfering with each other (as can be seen bellow).

NE_10647033_0-1680782596734.png

 

I have tried a lot of different things but am on the edge of giving up on using a complex splitting "plane"/surface and simply going with a simple straight one instead. This is my last ditch effort to see if anybody knows how to solve this.

(Files attached below)

Thanks!

 

 

Best answer by tbraxton

You are using an educational license, so most here will not be able to open your part.

 

It is possible to build what you want using Creo but it is a bit tricky to troubleshoot without the model.

 

Based on your description of the issue I would try extending the handle surfaces beyond the split surface

 

Then offset them to the thickness needed. I would use offset, not thicken.

 

Use the split surface to trim the quilt(s) before merging them together. You will need to merge the inner, outer, and split surface together to create a closed quilt that will solidify..

3 replies

kdirth
21-Topaz I
kdirth21-Topaz I
21-Topaz I
April 6, 2023

I am unable to open the model as it is made on an educational version of Creo.  Most people on here will have the same issue.  Without the model. I cannot investigate what is going on in your model.

 

From my experience, I would take a simpler route.  I would create the entire shell then project a silhouette curve to use for splitting the model.  This model can then be inherited into the front and back models where the split cut can be made, and additional features added.

 

A couple other comments:

  • Tangent at split may not work if a texture is to be added to the mold.
  • The Lip command (not found in the ribbon) can quickly add alignment features around the edges.
There is always more to learn.
N
NE_106470331-VisitorAuthor
1-Visitor
April 6, 2023

Thank you for letting me know about the limitations with the education package. I appreciate the heads-up.

 

I've worked with Fusion 360 before, which has a 'split body along surface' command, but I haven't been able to find an equivalent in Creo. Could you please explain how you suggest I approach this? I'm also concerned about finding the best place to split it since it needs to be suitable for injection molding.

 

I see now that a sharp draft angle wouldn't work for mold removal if it is to have a texture, but since the model should be smooth having a tangent at the edge should be fine right?
I'm not very experienced with the configuration editor, so I wasn't able to figure out how to use the Lip command.

 

Thank you again for your help. I truly appreciate it."

kdirth
21-Topaz I
kdirth21-Topaz I
21-Topaz I
April 6, 2023

A surface can be used to cut a model using the Solidify command.

 

Split body can also be used to cut the model into two different body parts.

 

There is always more to learn.
tbraxton
22-Sapphire II
tbraxton22-Sapphire IIAnswer
22-Sapphire II
April 6, 2023

You are using an educational license, so most here will not be able to open your part.

 

It is possible to build what you want using Creo but it is a bit tricky to troubleshoot without the model.

 

Based on your description of the issue I would try extending the handle surfaces beyond the split surface

 

Then offset them to the thickness needed. I would use offset, not thicken.

 

Use the split surface to trim the quilt(s) before merging them together. You will need to merge the inner, outer, and split surface together to create a closed quilt that will solidify..

N
NE_106470331-VisitorAuthor
1-Visitor
April 6, 2023

I appreciate the heads-up about the limitations with the education package!

 

I decided to run a quick test based on your suggestion, and I'm happy to report that it seems like it will work perfectly for my needs. I'm not sure how I overlooked this as a potential solution, but perhaps I was experiencing some tunnel vision due to being new to surface modeling.

 

Your help has been invaluable and has probably saved me a lot of time! I appreciate your willingness to share your knowledge and expertise with me.

 

N
NE_106470331-VisitorAuthor
1-Visitor
April 6, 2023

It worked. Everything is now perfectly lining up.
NE_10647033_0-1680803583599.png

NE_10647033_1-1680803706742.png

Thank you for the help

 

tbraxton
22-Sapphire II
tbraxton22-Sapphire II
22-Sapphire II
April 6, 2023

This is an example of a similar design for molding. @kdirth is offering solid advice to create a master model of the outer surfaces ( making sure it can be offset to the required thickness) and then split it.

 

This is a surface master used to create the 3 molded parts shown in the second picture.

tbraxton_0-1680786777868.png

 

tbraxton_1-1680786792777.png

 

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