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A
agaribay1-Visitor
1-Visitor
June 23, 2015
Solved

How to make copy of PART & DRAWING

  • June 23, 2015
  • 6 replies
  • 51118 views


I am trying to create a copy of an existing drawing giving it a new number.

 

I have set the option:  rename drawings with object  =  both

 

Both the Model and the Drawing have the same part number and are open / in session.

 

I "SAVE AS" - (Save as Copy), and enter the NEW PART NUMBER.

 

I end up with a New Drawing, but no new part.  The part in the drawing still shows the Old Part Number.

 

Any ideas as to what I am doing wrong?

CREO 2.0

 

Thanks.

 

-Art

Best answer by Clipper_captain

Open the drawing and the part in Creo; make sure the part window is active. At this point, do file / save as / save a copy. In the message portion of your Creo window, you should see the rename of the part and drawing being complete. In case you miss it, you can check the message log and find it there.

Have a good one.

6 replies

M
Mahesh_Sharma22-Sapphire I
22-Sapphire I
June 23, 2015

Art,

All steps seems good.

Try to create a part as a.prt and drawing of A.prt as A.drw.

Save in same location and close part and drawing.

Open part A and Save as to B

Check for B.drw.

There are only three conditions for this:

1. Name of part and drawings should be same.

2. Saved in same location.

3. Config options should be set.

J
Joe_Mama1-Visitor
1-Visitor
March 28, 2018

DID not work

S
23-Emerald III
StephenW23-Emerald III
23-Emerald III
March 28, 2018

Do you have the config option set correctly? (rename drawings with object  =  both)

Was the drawing and the model named exactly the same? (other than the extension)

 The save must be done on the part.

C
Chris321-Topaz I
21-Topaz I
June 24, 2015

Are you doing save as on the part or the drawing? You need to do the save as on the part.

    D
    23-Emerald III
    Dale_Rosema23-Emerald III
    23-Emerald III
    June 24, 2015

    Do you have Windchill? If so, I am not sure.

    If you do not have windchill, I save a copy of both the part and the drawing in the file folder where they are located with a naming convention of:

    zzzzold_file_name.prt

    zzzzold_file_name.drw

    I then open both the part and the drawing (the name without the zzzzz prefix) and do a rename of both the drawing and the part. Rename old_file_name.prt/drw to new_file_name.prt/drw. After saving both, I then go back into the folder and rename the zzzz files and remove the zzzzz.

    Then the old part still opens and it should and the new part with it's drawing opens as it should.

    Thanks, Dale

    C
    Chris321-Topaz I
    21-Topaz I
    June 24, 2015

    If you have Windchill then another technique is to just open both in session and do a rename on both and save. That's it. Renaming both items through the Creo interface in a Windchill environment is the same as a save as.

    Make sure to have any next higher assemblies you want updated in session or make sure to erase everything if you don't want next higher assemblies updated.

    C
    Clipper_captain12-AmethystAnswer
    12-Amethyst
    June 24, 2015

    Open the drawing and the part in Creo; make sure the part window is active. At this point, do file / save as / save a copy. In the message portion of your Creo window, you should see the rename of the part and drawing being complete. In case you miss it, you can check the message log and find it there.

    Have a good one.

    A
    agaribay1-VisitorAuthor
    1-Visitor
    June 24, 2015

    Thanks guys.  I ended up making a copy of the Drawing and Part in another directory.  I then opened both and renamed in session.  done.

    I will have to try SAVEAS with the Part Window Active as I had the Drawing Active.

    We do not use Windchill.  We're using Agile Engineering Collaboration.


    M
    Mahesh_Sharma22-Sapphire I
    22-Sapphire I
    June 24, 2015

    Art,

    As you manage to get it working, you may mark the appropriate answer as correct in the post.

    Y
    yyang-41-Visitor
    1-Visitor
    November 24, 2015

    that is to say the prt and drawing must be in the same folder, and our company seperate the prt folder and drawing folder ,i think it is not correct .do you think ?

    M
    MartinHanak24-Ruby III
    24-Ruby III
    November 24, 2015

    Art,

    the description of rename_drawings_with_object option tells us ... options controls whether the system copies associated drawings automatically with parts and assemblies. This means you have to copy the part, not the drawing !!!

    MH

      D
      Deepakjohsh13-Aquamarine
      13-Aquamarine
      November 5, 2019

      Thank you Martin!!

      I think this should have been marked as a solution.

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