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jyan-31-Visitor
1-Visitor
July 23, 2015
Solved

Family Table Assembly Don't Get Regenerate

  • July 23, 2015
  • 4 replies
  • 3069 views

Hi,all guys:

I have a question about the family table regeneration issue.

I have a task to create a bent which contains panels and columns(see picture 1#), the variation parameter of this bent is the height .In height 1 and 2, there should be 2 panels(girt_plate &girt_plate_1) ,and 3 panels( girt_plate & girt_plate_1&girt_plate_parametric) for height 3 and 4.

1.jpg

2.jpg

That means we need girt_plate_parametric to be disappeared in height1 and 2 and shown in height3 and 4, so I made a family table , see below screen shot.

3.jpg

After I save this model then re-open , then choose new instance, double-bay-bent_D25_FHR3, the model just cannot regenerate. You may see that the columns don’t change when the height changes. The columns’ length do have relation with height.

3.png4.png

8.jpg

But when I firstly open the generic model then change the parameter, the model will regenerate, then I go to family table and open the double-bay-bent_D25_FHR3, it is the right bent I want.

The problem is this bent should be install to a high level assembly, so when I insert the bent and choose the right one , this one should be the one I want with all component at right size.

I am so appreciate anyone who could help on this.


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Best answer by gkoch

Yes, I see:

This code was not intended for Relations, but for Pro/PROGRAM

(in fact relations are a subcomponent of the program, but not the part where components are added)

You will find it under Tools > Model Intent > Program and then use Edit Program in an old Menu Manager Menu:

program_access.jpg  program_menu.jpg

Here is a functional example I created a couple of years ago - I just removed a couple of parts and assemblies inserted at the end.

The input section prompts the user for input of a boolean parameter when regenerating the assembly, the relations section is what you see with Relations and the ADD sections reflect the features/components of type PART, SUBASSEMBLY and FEATURE. This is where you can skip features using the IF-conditions.

The MASSPROP section at the end was the only way in the past to make Pro/ENGINEER calculate mass properties. It is still functional, but by now concurrent methods exist, that are easier.

I will also update the existing article CS35523 (How to suppress components in assembly mode using Program in Pro/ENGINEER Wildfire 5.0) in the PTC Knowledge Database with this information.

VERSION 2.0
REVNUM 143
LISTING FOR ASSEMBLY PROGRAM

INPUT
MIT_ACHSE YES_NO
"should the subassembly achse.asm be implemented?"
END INPUT

RELATIONS
d0:2 = d4:0
D1:1=d1:8
D0:1=d0:8
d5:2=d3:0
END RELATIONS

ADD PART PLATTE
INTERNAL COMPONENT ID 1
END ADD

IF (MIT_ACHSE == YES)
     ADD SUBASSEMBLY ACHSE
     INTERNAL COMPONENT ID 2
     PARENTS = 1(#1)
     END ADD

     EXECUTE ASSEMBLY ACHSE
     END EXECUTE
END IF

<... here I removed the other components that appear the same way as the PART PLATTE and SUBASSEMBLY  ACHSE>

MASSPROP
END MASSPROP

4 replies

gkoch2-Explorer
2-Explorer
July 31, 2015

Have you tried with Pro/PROGRAM in the assembly?

IF (FILL_ST... > 85)

ADD PART XYZ

INTERNAL COMPONENT ID ###

END ADD

END IF

    jyan-31-VisitorAuthor
    1-Visitor
    August 3, 2015

    Thanks so much Koch, but when I input that code in the program, it turns out to be an error, please see the screenshot. 11.png

    looking forward to your further supporting!

      gkoch2-ExplorerAnswer
      2-Explorer
      August 3, 2015

      Yes, I see:

      This code was not intended for Relations, but for Pro/PROGRAM

      (in fact relations are a subcomponent of the program, but not the part where components are added)

      You will find it under Tools > Model Intent > Program and then use Edit Program in an old Menu Manager Menu:

      program_access.jpg  program_menu.jpg

      Here is a functional example I created a couple of years ago - I just removed a couple of parts and assemblies inserted at the end.

      The input section prompts the user for input of a boolean parameter when regenerating the assembly, the relations section is what you see with Relations and the ADD sections reflect the features/components of type PART, SUBASSEMBLY and FEATURE. This is where you can skip features using the IF-conditions.

      The MASSPROP section at the end was the only way in the past to make Pro/ENGINEER calculate mass properties. It is still functional, but by now concurrent methods exist, that are easier.

      I will also update the existing article CS35523 (How to suppress components in assembly mode using Program in Pro/ENGINEER Wildfire 5.0) in the PTC Knowledge Database with this information.

      VERSION 2.0
      REVNUM 143
      LISTING FOR ASSEMBLY PROGRAM

      INPUT
      MIT_ACHSE YES_NO
      "should the subassembly achse.asm be implemented?"
      END INPUT

      RELATIONS
      d0:2 = d4:0
      D1:1=d1:8
      D0:1=d0:8
      d5:2=d3:0
      END RELATIONS

      ADD PART PLATTE
      INTERNAL COMPONENT ID 1
      END ADD

      IF (MIT_ACHSE == YES)
           ADD SUBASSEMBLY ACHSE
           INTERNAL COMPONENT ID 2
           PARENTS = 1(#1)
           END ADD

           EXECUTE ASSEMBLY ACHSE
           END EXECUTE
      END IF

      <... here I removed the other components that appear the same way as the PART PLATTE and SUBASSEMBLY  ACHSE>

      MASSPROP
      END MASSPROP

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