12-Amethyst

Solved

Help: Creo 2.0 Save a Copy, drw has lost parameters.

Forum|Forum|12 years ago
March 25, 2014
4 replies
4084 views

I require help.

I have created a drawing template that calls parameters from Windchill 10.1 (3D Model state: &PROI_RELEASE and rev: &PTC_WM_VERSION, drawing state: &PROI_RELEASE:D, ver: &PROI_VERSION:D, and rev: : &PTC_WM_REVISION:D ...

It was pointed out to me today that when a user performs a "Save As" "Save a Copy" from Creo on the part, not all the parameters copy in the copied drawing - many turn into the text ***.

^Original

^Copy ... note: State for the 3D model, and the drawings state and version converted to ***

Why does this happen? How can I get it to save correctly?

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General

Best answer by dgoodland

SOLVED!

Rajeev @ PTC finally found the issue... The Legacy Pro/Intralink parameters are not able to carry over. So I had to replace with the Windchill updated parameters (Which give the exact same values).

For STATE: &PTC_WM_LIFECYCLE_STATE:D WAS &PROI_RELEASE:D

For VERSION: &PTC_WM_ITERATION:D WAS &PROI_VERSION:D

For REVISION: &PTC_WM_REVISION:D WAS &PROI_REVISION:D

Note: the 😄 makes it drawing parameter specific, and without it is taken from part.

Hope this makes sense!

Daniel...

T

TomD.inPDX

17-Peridot

Likely, this is because Windchill doesn't have a default value for those fields. It has to come from the new entry.

You might consider submitting a support case to learn how PTC intended this functionality to work seamlessly.

D

dgoodland

Author

12-Amethyst

Okay... my current work around is weak - but works. I made txt files for the cells that go wrong... the user then edits the properties of the cell and "Open"s the appropriate txt file to populate with the correct text with Parameter.

Yes - this could be made into a mapkey that does it all - but it is not supposed to be a solution.

D

dgoodland

Author

12-Amethyst

Just to clarify:

the parameters are literally lost and not just "empty" ... the values of the parameters are not ***, the parameters are replaced with the text ***. So it is not just a case of changing values for the paramerters.

D

dschenken

1-Visitor

It fails because the result of a Save As is a new file, which has no parameters supplied by Windchill. It would be nice if PTC caused the field contents to be changed from "&parameter" to "parameter-missing" to make it easier to understand the problem. I guess the Windchill parameters and a number of other internal values are not copied to make it easier when the part is checked in; instead of having to check to see if they exist in a new file and then modifying them, they are always just added.

D

dgoodland

Author

12-Amethyst

Better would the values be "blank" as a worst case. But it's a new part and drawing - they should exist!

Try this: Start a new part and make its drawing... the parameters work, and they have not yet been checked in either.

D

dgoodland

AuthorAnswer

12-Amethyst

SOLVED!

Rajeev @ PTC finally found the issue... The Legacy Pro/Intralink parameters are not able to carry over. So I had to replace with the Windchill updated parameters (Which give the exact same values).

For STATE: &PTC_WM_LIFECYCLE_STATE:D WAS &PROI_RELEASE:D

For VERSION: &PTC_WM_ITERATION:D WAS &PROI_VERSION:D

For REVISION: &PTC_WM_REVISION:D WAS &PROI_REVISION:D

Note: the 😄 makes it drawing parameter specific, and without it is taken from part.

Hope this makes sense!

Daniel...

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